Tool library setup in Fusion

00:02

Tool library set up in Fusion 360.

00:07

After completing this video, you'll be able to

00:09

identify tool, geometry and holder requirements. Create a new tool, library,

00:14

copy and edit library tools,

00:16

create a new end mill and define tool parameters for feeds and speeds.

00:22

Before we get into setting up our tool library and fusion 3 60.

00:26

I think it's important that we take a look

00:28

at the physical tools to better understand tool,

00:30

geometry and holder requirements.

00:33

As there are many different types of tools and holders on the market,

00:37

it's important that we understand what our machine requirements are and

00:40

what tools and holders are available to us in our shop.

00:44

So let's go ahead and hop into the shop and take a look at tools and holders

00:54

now that we have a good idea about tools and holders in their physical requirements.

00:59

Let's go ahead and take a look at how we can set this up digitally in fusion 360.

01:04

Now, it's not required that we have a design open.

01:06

So I'm gonna close our caliper design showing that we have an untitled document

01:11

because all of our tool data is going to be saved independent of our design.

01:15

We're gonna begin by navigating from the design workspace to manufacture

01:20

and then I'm gonna first change the units.

01:22

In

01:22

this case, we're gonna use inch units

01:25

while once again, that's not a strict requirement.

01:28

It does help to make sure that we identify the units that we want to

01:31

use in our design as it will have an effect on our tool library.

01:36

Then we're gonna navigate to manage and select tool library.

01:40

Now it's important to note that there are a couple

01:42

of different places that we can save tool libraries.

01:44

In fusion 3 60

01:46

we have a dedicated fusion 3 60 library that's gonna have some sample tools for us.

01:52

Things that we can grab copy, paste and modify as needed.

01:56

We also have a local library which will be saved on your local machine

01:60

and then we have a cloud library.

02:02

Also note at the very bottom that we have an option to download vendor libraries.

02:07

This could be extremely helpful as you can access

02:09

tools that have already been set up by tools.

02:11

In

02:12

this case, we want to take a look at the basic process.

02:16

I do want to note that if you do not see cloud available in your tool library,

02:20

you can go to your user preferences.

02:22

After we close the tool library,

02:24

go up to your user preferences,

02:26

make sure that we navigate to the manufacture workspace and enable cloud library.

02:32

Once we have that set up. We can go back into our tool library and we can take a look

02:37

at the very top. We have documents and untitled.

02:40

This is where any tools used inside of a specific part will be accessed

02:45

for our purposes.

02:46

We're gonna store our new library on the cloud, but you can do it locally as well

02:52

when we open up our cloud section.

02:54

If you've never created a tool library before,

02:57

you're not going to see anything here.

02:59

In order to create your own tool library,

03:01

we can right click on cloud and select new library.

03:05

Ultimately, what we're gonna be doing is importing a tool library,

03:08

but it's important that we understand how to set it up for ourselves.

03:12

So I'm gonna simply call this sample library because we aren't going to be using it.

03:18

Once we have our sample library in place,

03:21

there are two main ways that we can get tools and holders into our library.

03:25

One way is to create them new from scratch and

03:27

the other way is to copy them from another library.

03:30

First, let's take a look at copying them from the fusion 3 60 library.

03:35

We're gonna go into cutting tools inch

03:38

and notice.

03:38

Currently it says the selected library is turned off fusion 3 60 changes,

03:44

the opacity.

03:45

In this case, this library is shown in gray

03:47

and we need to enable it or turn it on.

03:50

This is specifically done.

03:52

So that way we don't have to load all the tools into our program.

03:56

Once we have this set up, we wanna make sure that we go to our milling section.

04:01

We want to select our Fusion 3 60 library and we're gonna turn all libraries on.

04:06

This is gonna bring everything in from the fusion 3 60 sample.

04:10

Next, we're gonna filter by milling

04:13

flat and mill and you can see everything here is sorted by inch or metric units.

04:19

We're gonna take a look at a half inch flat end

04:21

MLL and then we're going to right click and select copy tool

04:25

from here.

04:26

We want to go into our sample library in the cloud, right click and paste the tool.

04:31

When we paste this tool, it's important to note that the filters are still active.

04:36

So let's make sure that we do clear all of our filters

04:39

in the tool library.

04:40

We have an info section which will give

04:42

us information about the tool specifically its description,

04:46

vendor product ID and a link if one is

04:48

available and then general parameters about the tool.

04:51

And if we scroll down, we can see feeds and speeds

04:54

at the bottom center, we also have cutting data presets.

04:58

And you can see that for cutting data,

04:60

we have a default preset and below that we have ones for aluminum slotting,

05:04

roughing and finishing.

05:06

For example,

05:07

these are gonna be helpful as it changes things like

05:10

the lead in and lead out the feed per tooth.

05:12

The cutting feed rate surface speed and the R PM.

05:16

These can all be customized individually when we're

05:19

talking about adding them to a tool path.

05:21

But it is important that we get a good

05:22

baseline when we're setting up our tool library.

05:25

If you want to make any changes, you can right, click on the tool and select edit tool

05:30

from here. We can make adjustments to the general properties

05:34

specifics on the cutting.

05:35

For example, if we have a four flute tool that has a specific coating,

05:39

we can set that up here.

05:41

We can also modify how far the tool sticks out

05:44

below the holder by modifying things like length below holder.

05:48

There's information for cutting data to modify our feeds and speeds.

05:52

But once again note that these will be stored in cutting data presets.

05:55

So if you want to modify things like aluminum roughing,

05:58

make sure you preselect that cutting data.

06:01

And finally,

06:02

we have a post process tab which will determine things like the tool number.

06:05

This is an important aspect as we want to make

06:08

sure it matches the tool number inside of our tool crib

06:11

and that it automatically updates the length and diameter offset values.

06:15

Those will be extremely important as we get down

06:18

the line and modify things like cut or compensation.

06:21

We're going to accept this tool and then we're gonna take a look

06:23

at a way that we can create our own tool from scratch.

06:26

And then ultimately import a library

06:29

to create our own tool from scratch.

06:30

We want to make sure that we're in the library where we

06:32

want that tool to be contained and then select the plus icon.

06:37

Once we select plus, we'll have to determine what type of tool we're creating.

06:41

This can be everything from a blank holder, a probe,

06:44

cutting options for things like water jets and laser cutters.

06:48

We have turning tools and then we have hole making and milling tools.

06:52

Let's go ahead and create a flat end mill.

06:55

Once we do that, we can enter information, for example, the description

06:59

and we're gonna call this a 0.25 flat end mill, just a generic name.

07:06

Then we can go into our cutting data and modify the parameters.

07:10

In this case, we want to make sure that the diameter is 0.25.

07:13

We're gonna tab to the shaft diameter

07:15

which automatically updates to the tool diameter

07:18

tab to the overall length. In this case, we'll set it at 2.5 inches

07:22

length below holder will set to two

07:24

our shoulder length inch and a quarter

07:26

and our flute length will be three quarters of an inch.

07:29

This data should come directly from a tool manufacturer.

07:33

If you're buying a tool off the shelf,

07:34

you need to make sure that your digital tool matches the physical tool.

07:39

In this case, the tool doesn't currently have a holder. If we select holder,

07:43

we can pick from a default holder located in any of our libraries.

07:47

You'll notice at the very bottom we have holder inch.

07:50

And if we drop that down, you can see that it shows us BT and CT 40

07:56

we can select generic holders

07:58

as we go down the line. We wanna make sure that the holder does fit the diameter.

08:02

In this case, we're going to use AC T 40.25 by 1 38.

08:07

And we'll select that holder.

08:09

When we do that, you can see it's placed inside of our design.

08:13

We would then want to make sure that we go back to the

08:15

cutting section and make sure that the tool is extended below the holder,

08:20

the correct amount.

08:21

In this case, I'm gonna set it at one inch

08:24

and make some adjustments, the shoulder length set that at one inch as well.

08:28

So now you can see it modifies the tool's position in the holder.

08:32

This is important for us for collision

08:34

checking to ensure that the non cutting portion

08:36

of the tool and the holder did not intersect our stock or any work holdings.

08:41

And finally make sure that we do adjust the tool number length offset

08:44

and diameter to make sure that those are all correct for our uses.

08:48

Once we accept that, now the tool will be stored inside of our library.

08:53

Once again, we need to make sure that our feeds and speeds are correct.

08:56

And this is general information that will come from the tool manufacturer and

08:60

then you can validate it and prove it out through sample programs.

09:03

But now let's talk about how to import a tool library

09:07

from here. I'm going to go to my cloud option.

09:09

Right, click and select import libraries.

09:12

Navigate to the location where you save the precision machine and caliber dash host

09:16

dot tools file and select open.

09:19

This is going to place this tool library in your cloud or local library.

09:23

Wherever it was imported to

09:25

this library contains ac

09:33

All the tools in this list.

09:34

With the exception of the drills have hot links directly to the

09:37

website.

09:39

When you set up your own tool library,

09:41

make sure that you are using tools that you do have available at your shop.

09:45

For example, in this tool list, tool number one is a 90 degree spot drill.

09:49

But in reality,

09:50

if you're using 100 and 18 degree job or drill bits for tool three and tool four,

09:55

you would want to make sure that you do have

09:57

a spot drill that has 100 and 20 degree angle.

10:00

So these are things that are not going to be set up

10:03

for you because every shop has different tools available to them.

10:06

If you want to go through the host tooling website,

10:09

you can take a look at the product links for the various tools.

10:12

Again, with the exception of the drill bits,

10:14

these are standard drill bits that have come from the fusion 3 60 library.

10:18

If you follow the product links, you can go to the

10:20

website and navigate to feeds and speeds information provided by ho

10:25

what we have here is the max spindle speed set on all the tools at 8100 R PM,

10:30

which is the max spindle speed.

10:32

On a HO

10:32

VF two,

10:34

you can obviously adjust these values based on your requirements,

10:37

but everything has been currently set with a HO

10:39

VF two max limit.

10:42

You can see that this tool list contains information for spot drill,

10:45

a champ for mill,

10:47

a handful of drill bits,

10:48

a quarter inch flat end mill, a shell mill for facing.

10:52

And then we have a flat end mill that we're using for roughing and finishing

10:55

a bull nose mill and followed up by a quarter 20 tap.

11:00

All this information will be used throughout our course,

11:02

but make sure that you do go into each tool, review the information

11:06

and navigate to the host website to identify the

11:08

tool and the feeds and speeds from them.

11:11

For now, let's go ahead and close this and because this is saved in the cloud,

11:14

nothing has to happen with our design, we can go ahead and move on to the next step.