Update toolpaths and documentation

00:02

Update tool paths and documentation.

00:05

After completing this video, you'll be able to

00:08

regenerate tool paths after a model change,

00:10

update a setup sheet and post process a CAM setup

00:16

in fusion 3 60. Let's carry on with the data set. From our previous example,

00:20

we took a look at what an engineering change

00:22

order can potentially do to our CAM program.

00:26

Now that we've updated the 3D model and we

00:28

now are ensuring that we're matching the correct dimension.

00:32

We need to make sure that we update not only the tool pass and fusion,

00:36

but that we also update our NC program,

00:38

the NC file that's going out to the machine as well as our setup sheet.

00:42

While the setup sheet is likely not going to change,

00:45

it is important that our tool paths are correct,

00:48

especially the tool path where we bore and finish off the area for the piston.

00:53

So to get started with

00:55

one selected, we want to make sure that we go to actions and select generate

00:59

this will allow fusion 3 60 to go back through and regenerate each tool path

01:04

because no geometry has changed in terms of

01:07

the edges or faces from the original model,

01:10

the sketches were updated.

01:12

So the geometry just simply changed size,

01:14

all the tool paths should regenerate without problem.

01:17

Again,

01:18

if you did happen to do some manual modifications where

01:21

you created a sketch and extruded to a larger size,

01:24

that would require a

01:26

reelection in whatever affected tool paths come about.

01:29

Remember that two D tool paths are not model aware.

01:32

They're looking for specific selections, whether it's a face,

01:35

a contour or a silhouette.

01:38

In this case,

01:39

everything has been updated because it was modified at the original sketch.

01:43

The next thing that we need to do is note that the in this case,

01:46

the NC program is currently out of date

01:50

in order to update that,

01:51

what we need to do is go in and post process this and create a new setup sheet.

01:57

When we post process this,

01:58

we are going to overwrite this all the locations where it's currently saved

02:03

when we post process it.

02:04

In my case,

02:05

it's going to a temporary folder and it's going to overwrite

02:08

the design that was there because I'm using the same program.

02:12

However,

02:13

something that we should be aware of is that there's no way for us to

02:16

differentiate the difference between this program and

02:19

the original one which we just overwrote.

02:22

So it can be dangerous for us to just simply repost with the same number.

02:26

Something that we can do is we can add comments to our setups and tool paths

02:30

to make sure that it is known that these are updated based on a change in geometry.

02:35

The way that we can do this is by right, clicking on the setup.

02:38

In this case, what we wanna do is we want to add a new comment or note

02:43

close to the bottom of this list. We have edit notes

02:46

and then we're gonna add a note

02:48

and say the piston bore

02:51

updated to 1.065 rev B.

02:56

This comment is going to be posted in the NC code.

03:00

However, note that it doesn't affect the NC program.

03:03

It doesn't think that it's out of date

03:05

even though the code will be different.

03:08

The next thing that we want to do is we want to go into that finish bore tool path.

03:11

We're gonna right click and we're gonna put a note here as well.

03:15

So we're gonna say bore size change

03:18

and we're gonna say to 1.065 rev B,

03:22

once again, it never hurts for us to add or have these notes.

03:26

There is another way that we can do this to

03:28

ensure that it's visible at the top of our program.

03:31

And that's by going to our setup and creating what's called a manual NC.

03:35

Manual NC is essentially a way for us to automatically put in specific code.

03:41

In this case,

03:42

we're gonna do a comment but notice that we can put stop or optional stop dwell.

03:47

We can measure a tool we can stop or start the chip transport.

03:51

There are a bunch of different things that we can put in

03:54

different portions of our code that behave like a tool path.

03:58

So in this case, we're going to put a comment in

03:60

and we're gonna say

04:01

piston bore update

04:08

B,

04:09

we'll say, OK.

04:11

And now we're gonna drag that to the very top of our tool paths.

04:14

So this happens before we ever rough the caliper

04:18

because we added a new tool path.

04:21

Now, this is telling us that our NC program is out of date.

04:24

We're gonna right click and we're gonna post process this.

04:27

We're gonna say yes and we're gonna take a look at the code.

04:31

Now you can see here, we put a comment at the very top piston bore update to 1.065 rev B.

04:39

The reason that we did it with this option.

04:42

When we go into our NC program,

04:45

there are different options that allow us to put comments inside of our programs.

04:51

For example, inside of the formats, option

04:54

notice here that we've got different options for showing the version,

04:58

showing notes.

04:59

And by default,

04:60

some of these options might be turned off if we

05:03

include show notes and we repost this and overwrite.

05:07

Now, when we post this,

05:08

what we're going to see is that we will be able to

05:10

see the notes that are in there for the tool path.

05:12

However, the note for our setup is not showing

05:15

using the control F or find I'm gonna type in

05:18

the word bore and I'm gonna look through the code

05:21

semi

05:22

rough bore. We're going to go down to the finish bore.

05:25

And now we can see here's the note that we included

05:27

with that tool path bore size change to 1.065 rev B.

05:32

So even though we placed a note at the very

05:35

top level piston bore updated to 1.065 rev B,

05:39

it was only shown at the tool path level.

05:42

Now, the reason for this,

05:44

it varies from different machine to different machine

05:47

based on the post processor you're using.

05:49

But the notes at the setup level will be displayed on our set up sheet.

05:53

Let's go ahead and edit this NC program one more time.

05:56

Now there's one other bit of information that we definitely should include

06:00

and that's gonna be the part number and revision.

06:03

Now, since this part actually had to be updated and it now has A

06:07

B

06:07

that is critical information that should be at the top of our program.

06:11

So the place that we should put this is in our NC program under the comment.

06:15

So this is going to be CC dash sp dash fr for front dash 001.

06:22

And we'll put a space for REV B.

06:25

Uh Once we have that information, we'll say, OK,

06:28

notice that. Now our NC program is out of date

06:31

if we post process this one more time and once again, overwrite our code

06:35

now,

06:35

we should see that the part number and rev is going to be listed at the top of our code.

06:40

We still have our notes here from our manual MC.

06:43

And if we go ahead and do another search through the code,

06:46

our piston board update for the specific tool path will be there as well.

06:50

Now that we've updated and we've taken a look at where the notes,

06:53

the manual NC and the comment in our NC program show up.

06:57

We need to go ahead and create a setup sheet once more.

07:00

Uh Once again, we're gonna overwrite the setup sheet that's already in here

07:04

and select save.

07:06

Now, we're not gonna get a prompt to overwrite it.

07:07

It just simply does update the content.

07:11

And as we look through our setup sheet, we can see here.

07:13

Now, the program comment has our part number including REV B

07:18

as we go through and we take a look, all our tools should still be the same.

07:21

Nothing changed here.

07:23

Note that our setup note does display here on our set up sheet,

07:27

piston bore updated to 1065 RB.

07:30

And the notes that we have for our operations,

07:33

any notes that were placed here will show up on the set up sheet as well.

07:37

So while they do show up in certain places in

07:40

the code specifically for the tool path itself for the operation

07:44

and for our manual NC, as well as for our comment,

07:48

the information that we place on the set up will show up on the set up sheet as well.

07:53

So again,

07:54

it can't hurt to have that information as many places as possible

07:59

to ensure that you are creating the correct part based on your program

08:04

at this point.

08:04

Let's go ahead and close this out,

08:06

make sure that everything is saved before moving on.