Manual part inspection

00:02

Manual part inspection.

00:05

After completing this video, you'll be able to

00:07

review part blueprint measure and record inspection dimensions

00:10

and enter manual inspection data infusion 360.

00:14

We'll measure each part at the end of each operation

00:17

and again at the end for a complete final inspection.

00:20

Now, every company has their own requirements,

00:23

uh telling them how many parts from each batch that they need to inspect

00:28

to reach the quality level that they're aiming for.

00:31

Now, we're only running a single part.

00:33

So we're gonna go ahead and check every single dimension on our blueprint.

00:37

We'll verify everything that we need to

00:39

for this operation after a visual inspection,

00:42

then we'll write those values down on our inspection sheet.

00:46

Our 1.19 inch mounting face measures right at

00:56

and this is well with intolerance.

00:57

Now, if it was off by some amount that we wanted to fix,

01:01

we would go to our

01:02

offset page

01:03

and we would make an adjustment.

01:05

We don't want to adjust the tool that is making that surface

01:08

because that's only gonna affect that one surface,

01:11

we want to bring all of our tools up and down together.

01:13

So we would make a work offset adjustments,

01:17

tool offsets only adjust that tools offset, work offset,

01:20

adjusts every tool that's being used for that operation.

01:24

Our G 55.

01:25

In this case to measure our 0.44 inch counter board depth,

01:29

we can make use of the depth measuring blade

01:32

at the end of our calibers.

01:33

Now, our tolerance is plus or minus 20 thou

01:37

which is well within the accuracy range of our calibers.

01:40

Now, if this depth needed to be measured within a few 10th of a thou,

01:44

we'd be using our depth micrometers.

01:46

One of the simplest ways to measure our

01:53

Now, if this counter board was too deep,

01:56

it was made by

01:58

tool five, our quarter inch and mill. So we could just bring tool five

02:02

up

02:03

on our tool offset page. We could adjust that length offset where

02:07

that would bring our tool up or down,

02:10

which would make our counter board depth go up or down.

02:14

Likewise, if we took our gauge pin and our and our counter board diameter

02:18

was too small or too large. We could add or subtract to our T five

02:24

diameter wear value to make this counter

02:27

or bigger or smaller.

02:29

And I'll just mention this right here. Uh kinda kinda lean in here and listen.

02:34

The only way we can adjust tools like this diameter wear at the control

02:39

is if we've set our compensation type to wear

02:44

in fusion 360 for that finished pass.

02:47

So if you're making all types of diameter wear adjustments,

02:49

but nothing's moving on the part,

02:51

we might not have selected the right compensation type when we

02:56

set up our tool in the first place inside fusion.

02:59

So make sure that that's set up properly. Typically, for me,

03:03

um I set it up for my finish passes to use the wear compensation

03:08

in my camp system

03:09

for more information on how to adjust features getting them

03:13

to come into spec using cutter compensation or tool diameter.

03:17

We

03:18

go check out re-watch that caliper op one inspection video.

03:23

Now with this second operation all inspected,

03:26

it's time for us to go back and do

03:27

a complete final inspection to make sure that nothing changed

03:32

and things can change

03:34

earlier. After OP one, we measured our piston board diameter as 1.064 inches.

03:41

If we had over tightened our vice

03:43

while holding our part in our second op soft jaws,

03:46

we could have crushed it, deforming this boar.

03:50

So we will go ahead and inspect all of our dimensions

03:53

and record what we have found on our inspection sheet,

03:58

paper, inspection sheets. Work great. We've used them forever,

04:02

but there are better, more modern tools available to us.

04:05

And we're gonna look at those options right now.

04:09

Now that we've manually inspected the caliper we want to make sure that we also

04:13

understand how to enter values back into Fusion

04:19

So inside of Fusion 360 we're going to select

04:22

all of the manual inspection dimensions that we created

04:25

right click and record manual inspection.

04:29

Because again, this is tied to a named view for OP two.

04:32

We need to hide our vice and soft jaw.

04:35

Notice that there is a dialogue on screen with the first dimension,

04:38

we can enter a value here or we can do it directly in the dialogue.

04:42

It's showing the nominal dimension as 0.6.

04:45

And you can see that we've got the tolerance range 0.55 to 0.65.

04:50

And when this is measured, it's a value of 0.6

04:53

you can see that it's within tolerance and we can select next to go to the next value

04:59

this was measured with a gauge pin.

05:01

So we don't have a manual dimension to enter,

05:04

but we do know that it passed the gauge pin test.

05:06

So we're going to go to 0.255

05:09

and select next.

05:12

Next, our whole distance between the caliper is going to be 2.75 as measured.

05:18

And again, we're going to select next.

05:21

Now as a test, if these holes were out of spec in this case,

05:25

we used gauge pins to measure.

05:26

But for example, if this was 0.32

05:29

we can see whether or not it's within spec,

05:32

can see the deviation value and the error amount.

05:35

If this was 0.15 we can see that it is within spec and the deviation is 0.0025. In

05:42

this case, since we did use gauge pins,

05:45

we're gonna enter the 0.313 value and move on to the next value.

05:49

Once again using gauge pins. Here, we're gonna enter 0.255

05:54

and select next

05:56

for the piston bore. We have a measured value of 1.064.

06:02

We can see that the deviation value is 001.

06:07

And we can select next

06:09

for the depth value this measured at 0.65.

06:13

And we can see that's coming in with zero error and zero deviation.

06:16

And we'll select next,

06:18

we have all the values recorded and you can see

06:21

that the results can be in a new inspection results.

06:24

And once we say, OK,

06:25

we now have a results folder listing all of those values.

06:29

These values will also show up on screen as green if they're within tolerance

06:33

and orange if they're out of tolerance.

06:36

So it's a great way for us to investigate the model and make

06:38

sure that everything is within spec based on the print that we're using.

06:43

We can also right click and generate what's called an inspection report.

06:47

We're going to select save and it's gonna generate

06:50

our inspection report with all of our measured values.

06:54

This will open up as an html document and we can investigate

06:57

all of the values entered whether or not they're within tolerance.

07:00

And if there is an error

07:02

note that fusion does have the available option to use Bluetooth calipers,

07:06

which will directly enter these values.

07:08

While we're recording them.

07:09

At this point, we can go ahead and go back into fusion 360.

07:13

Make sure that everything we've done to this point is saved before moving on.